How to extract force reactions using DPF inside mechanical ?
Vishnu
Member, Employee Posts: 222
✭✭✭✭
Comments
-
Below is a simple code to extract the Y Reaction using DPF inside mechanical
import mech_dpf import Ans.DataProcessing as dpf #Result Data analysis1 = ExtAPI.DataModel.Project.Model.Analyses[0] dataSource = dpf.DataSources(analysis1.Solution.ResultFilePath) #model my_model = dpf.Model(analysis1.Solution.ResultFilePath) #my mesh my_mesh = my_model.Mesh #Time list timelist = dpf.operators.metadata.time_freq_provider(data_sources=dataSource).outputs.gettime_freq_support().TimeFreqs.Data reaction = dpf.operators.result.reaction_force(time_scoping=timelist,data_sources=dataSource) Y_reaction = dpf.operators.logic.component_selector_fc(fields_container=reaction,component_number=1).outputs.fields_container.GetData()[0] print(sum(Y_reaction.Data)) #Release Locked RST my_model.ReleaseStreams()
0 -
Hello Vishnu,
Thanks for this.
Can we extract the results for total deformation at particular location for all the steps in the analysis and export it as csv??0 -
@prasadmsonar_123
You canLook at below code the dispfield_container is a field container which is a list of multiple fields (field for each time point)
and the fields in turn contains the data of displacement(x,y,z) for each node
now all you need to do is push the data to a CSV file:
import mech_dpf,csv import Ans.DataProcessing as dpf #Result Data analysis1 = ExtAPI.DataModel.Project.Model.Analyses[0] dataSource = dpf.DataSources(analysis1.Solution.ResultFilePath) #model my_model = dpf.Model(analysis1.Solution.ResultFilePath) #my mesh my_mesh = my_model.Mesh #Time list timelist = dpf.operators.metadata.time_freq_provider(data_sources=dataSource).outputs.gettime_freq_support().TimeFreqs.Data dispfield_container = dpf.operators.result.displacement(time_scoping=timelist,data_sources=dataSource).outputs.fields_container
1