How to add a table (from file) and assign it to a pressure load?

Erik Kostson

Say we have a pressure depending on x location and time in a csv file . How can we add this using scripting to a table, and then assign that table to a pressure load?

Erik Kostson

Below is one way of doing (change folder location as needed - and rest of script to adapt to needs):

model=ExtAPI.DataModel.Project.Model
analysis=model.Analyses[0] # refer to analysis
ns=ExtAPI.DataModel.Project.Model.NamedSelections.Children[0]
tablegroup=model.AddTableGroup(True)

mtable = tablegroup.AddTable()

with Transaction(True):
    filename = r'D:\\timexpress.csv'
    format = MechanicalEnums.Table.ImportFormat.Delimited
    settings = Ansys.Mechanical.Table.ImportSettingsFactory.GetSettingsForFormat(format)
    settings.Delimiter = ','
    settings.UseColumn(0, MechanicalEnums.Table.VariableType.Time, MechanicalEnums.Table.VariableClassification.Independent, 's', 'Time') \
        .UseColumn(1, MechanicalEnums.Table.VariableType.XCoordinate, MechanicalEnums.Table.VariableClassification.Independent, 'm', 'X Coordinate') \
        .UseColumn(2, MechanicalEnums.Table.VariableType.Pressure, MechanicalEnums.Table.VariableClassification.Real, 'Pa', 'Pressure')
    mtable.Import(filename, format, settings)
mtable.Name='mytable'

my_press=analysis.AddPressure() 

my_press.Location=ns

my_press.Magnitude = "mytable"